Gary, That's different. If one assigns the Voltage Property to the PWR/GND nets (P3V3VDC in this case) then the Xnet understands the discrete is really and termination and won't form the Xnet. Edit > Properties > (find filter set to "Nets") > Voltage = 3.3v, GND = 0V Dave Dave Seymour Ixia www.ixiacom.com<http://www.ixiacom.com> 919.267.4840 ________________________________ From: icu-pcb-forum-bounce@xxxxxxxxxxxxx [mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx] On Behalf Of Macindoe, Gary Sent: Wednesday, October 06, 2010 5:45 PM To: icu-pcb-forum@xxxxxxxxxxxxx Subject: [PCB_FORUM] Re: XNet dilemma Well, the net "P3V3VDC" is a member of the XNet "EEPROM_WP" for one example (3.3V & EEPROM write protect?). I don't think there is a reason to have xnets setup at all. I like to put the property Ratsnest_Schedule = Power_And_Ground on my power and gnd nets so that the rats look like this: [cid:image001.jpg@01CB6581.67FF9220] Instead of the rats going all over the place (yeah, I don't like filled pads either!). Regards, Gary MacIndoe Senior PCB Layout Designer Contract - Kelly Services Covidien EbD R&D 5920 Longbow Drive Boulder, CO 80301 303.476.7458 www.covidien.com From: icu-pcb-forum-bounce@xxxxxxxxxxxxx [mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx] On Behalf Of Shaw, Christopher Sent: Wednesday, October 06, 2010 3:28 PM To: icu-pcb-forum@xxxxxxxxxxxxx Subject: [PCB_FORUM] Re: XNet dilemma But what do you mean exactly by 'should not be there'? Chris From: icu-pcb-forum-bounce@xxxxxxxxxxxxx [mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx] On Behalf Of Dave Seymour Sent: Wednesday, October 06, 2010 4:25 PM To: icu-pcb-forum@xxxxxxxxxxxxx Subject: [PCB_FORUM] Re: XNet dilemma Edit> Properties (find filter set to Comps) > No_Xnet_Connection Or Specifically, remove the model from the component. Analyze > Model Assignment > Select the part and clear the model. ( this will come back if you reassign all models or auto assign) Hope this helps. Dave Dave Seymour Ixia www.ixiacom.com<http://www.ixiacom.com> 919.267.4840 ________________________________ From: icu-pcb-forum-bounce@xxxxxxxxxxxxx [mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx] On Behalf Of Macindoe, Gary Sent: Wednesday, October 06, 2010 5:17 PM To: icu-pcb-forum@xxxxxxxxxxxxx Subject: [PCB_FORUM] XNet dilemma Hey guys, I have some XNets in my design that should not be there. I asked the DE and he said that he didn't add them in the schematic (he doesn't even know about them). Does anyone know if there is a way to remove them in Allegro? Thanks for any help. Regards, Gary MacIndoe Senior PCB Layout Designer Contract - Kelly Services Covidien EbD R&D 5920 Longbow Drive Boulder, CO 80301 303.476.7458 www.covidien.com