Nagaraj, Symmetry is important - so is shielding. A modified stackup with cap (pad-only) layers top and bottom, with stripline construction, might be 1 pad 2 Gnd 3 Voltage 4 Sig 5 Gnd 6 Voltage 7 Sig 8 Gnd 9 Voltage 10 Pad Given your voltage requirements, you could make layer 9 into a ground, but it would be beneficial to make it a voltage plane to lower the impedance on one of your voltages. Or you could use it to distribute miscellaneous voltages. This construction gives you good shielding of the internal wiring, and a relatively constant impedance environment wherein you can switch layers to achieve routing with a minimum of impedance discontinuity. The stackup is immune to inter-layer crosstalk, and provides good HF decoupling of the power distribution system. It also gives you room on the board surface to embed EC changes or to avoid seriously congested areas. This use should be avoided if at all possible. Multiple ground (or power) planes are necessary because you have multiple signal layers and multiple voltage layers. Planes are needed adjacent to each signal layer to carry the return currents associated with fast risetimes. Without the planes, the return currents find their way onto nearby wires and you become the victim of crosstalk. If you have two signal lines between planes, they need to be routed at right angles to each other to minimize this problem. Ground planes are needed next to the voltage layers to provide low-impedance distribution of the voltages. Symmetry and shielding aren't everything. There are probably thickness constraints dictated by the enclosure into which the board must plug, and by manufacturing component lead protrusion requirements. There are 6 dielectric layers (those between signal and adjacent plane) that must be relatively thick to give you a workable signal impedance, and 3 (those between power and adjacent ground) that should be as thin as possible to provide low Z power distribution. I can't assess what this stackup would do to your manufacturability requirements. I have used similar construction successfully, but the board thickness was always a nagging concern. Regards Mike Nagaraj wrote: >Hi, > >We cann't Provide more GND Plane ( 4 ) as you specified and There is no >Provision for > >Splitting VCC2.5 in VCC3.3 Plane as There are 12V and 5 Volts are Already >Shared the VCC3.3 and 2.5 Plane > >Is there any Other Layer Stack up Can you Suggest. > >My Question is Why Multiple Ground are Very much Needed? > > > >Thanks in Advance > >Regards > >Nagaraj > > > >-----Original Message----- >From: si-list-bounce@xxxxxxxxxxxxx >[mailto:si-list-bounce@xxxxxxxxxxxxx]On Behalf Of >vasudevan.duraiswamy@xxxxxxxxxxx >Sent: Monday, December 02, 2002 5:34 PM >To: si-list@xxxxxxxxxxxxx >Subject: [SI-LIST] Re: 10 Layer Board Stack up > > > >Hi, > >It is correct that the layers should be symmetrical, to provide better >copper balancing, > >Power planes are generally defined by > > power integrity / decopling requirement > > impedance requirement > > Routability > >Your stack up can be modified as follows > >1)Top Signal 1 >2)GND >3)Signal 2 >4)VCC3.3 >5)GND >6)VCC2.5 >7)GND >8)Signal 3 >9)GND >10)Bottom Signal 4 > > > Routing, switch the signals between layer pair Top Signal 1 and Signal >2 or between layer pair Bottom Signal 4 and Signal 3 > > Don't switch over routing between Signal 1/2 to Signal 3 / 4 > >Incase of more routing layer requirement, make layer 4 & 7 also routing >layer , make layer 5 split power plane of VCC 3.3 & 2.5, make layer 6 as GND > >Regards, > >Vasudevan D >Technical Leader - PCB Design, CFT >Philips Software Centre Pvt Ltd, >Philips Innovation Campus, ># 01, Murphy Road, Ulsoor, >Bangalore - 560 008. India >Tel: +91 80 5579 000 extn : 5030 >fax : +91 80 5546 645 > > > > stephanie.goedecke+FromInterNet@ > philips.com To: >si-list@xxxxxxxxxxxxx > Sent by: cc: >(bcc: Vasudevan Duraiswamy/BTC/CFT/PHILIPS) > si-list-bounce@xxxxxxxxxxxxx Subject: >[SI-LIST] Re: 10 Layer Board Stack up > > >Classification: > 2002-12-02 02:48 PM > Please respond to > stephanie.goedecke+FromInterNet > > > > > > > >Hi, > >generally, the layers should be symmetrical. The details of the layout >depend on the >details of the board. > >Stephanie Goedecke > >Philips - SP3D Chip Design GmbH >Petersbrunnerstr.17 >82319 Starnberg / Germany > >Phone: +49-8151-270-160 >Fax : +49-8151-270-200 > > > >Hi , > >In 10 Layer Board stack How Multiple Ground Plane Will be More effective and >Why. > >Is there any Formula/Thumb rule behind this. > >most of my Critical Signal ( CLK) are Running at Signal Layer 1 >and My Board Stack up is > >Top >GND >Signal Layer 1 >VCC3.3 >GND >VCC2.5 >Signal Layer 2 >Signal Layer 3 >GND >Bottom > > > >Thanks in Advance. > >------------------------------------------------------------------ >To unsubscribe from si-list: >si-list-request@xxxxxxxxxxxxx with 'unsubscribe' in the Subject field > >or to administer your membership from a web page, go to: >//www.freelists.org/webpage/si-list > >For help: >si-list-request@xxxxxxxxxxxxx with 'help' in the Subject field > >List archives are viewable at: > //www.freelists.org/archives/si-list >or at our remote archives: > http://groups.yahoo.com/group/si-list/messages >Old (prior to June 6, 2001) list archives are viewable at: > http://www.qsl.net/wb6tpu > > > > > > >------------------------------------------------------------------ >To unsubscribe from si-list: >si-list-request@xxxxxxxxxxxxx with 'unsubscribe' in the Subject field > >or to administer your membership from a web page, go to: >//www.freelists.org/webpage/si-list > >For help: >si-list-request@xxxxxxxxxxxxx with 'help' in the Subject field > >List archives are viewable at: > //www.freelists.org/archives/si-list >or at our remote archives: > http://groups.yahoo.com/group/si-list/messages >Old (prior to June 6, 2001) list archives are viewable at: > http://www.qsl.net/wb6tpu > > >------------------------------------------------------------------ >To unsubscribe from si-list: >si-list-request@xxxxxxxxxxxxx with 'unsubscribe' in the Subject field > >or to administer your membership from a web page, go to: >//www.freelists.org/webpage/si-list > >For help: >si-list-request@xxxxxxxxxxxxx with 'help' in the Subject field > >List archives are viewable at: > //www.freelists.org/archives/si-list >or at our remote archives: > http://groups.yahoo.com/group/si-list/messages >Old (prior to June 6, 2001) list archives are viewable at: > http://www.qsl.net/wb6tpu > > > > > ------------------------------------------------------------------ To unsubscribe from si-list: si-list-request@xxxxxxxxxxxxx with 'unsubscribe' in the Subject field or to administer your membership from a web page, go to: //www.freelists.org/webpage/si-list For help: si-list-request@xxxxxxxxxxxxx with 'help' in the Subject field List archives are viewable at: //www.freelists.org/archives/si-list or at our remote archives: http://groups.yahoo.com/group/si-list/messages Old (prior to June 6, 2001) list archives are viewable at: http://www.qsl.net/wb6tpu