[PCB_FORUM] Re: components with attached routes

Running the following program should take care of it. 

I'm not sure if attachments will work on the forum, so I've attached the
file, but also included it below so you can cut/paste it into a file
called del_cline_prop.il.

One note that I ran into - if there are any fixed nets on the board,
this won't work on the parts they're associated with. So either unfix
all your nets, or at least unfix any nets going to the part you want to
move before running this program.


1) Load the attached program,  del_cline_prop.il  to current directory
or skill path.

2) At Allegro command line, type   skill

3) At Allegro command line, type   load "del_cline_prop.il"   (note: use
space and quotes)

4) At Allegro command line, type   exit

5) At Allegro command line, type   dprop


;
 ;       Tested on NT 13.6
 ;
 ;
 ;
 ; The following Skill routine will remove invisible
 ; properties from CLINES and VIAS.
 ; The intent of this Skill program is to provide
 ; users with the ability of deleting the invisible
 ; properties that SPECCTRA/SPIF puts on. This will allow the moving
 ; of symbols without the attached clines/vias once the
 ; design is returned from SPECCTRA if the fanouts were originally
 ; put in during an Allegro session.
 ;  
 ; To install: Copy del_cline_prop.il to any directory defined
 ;               within your setSkillPath in your 
 ;               allegro.ilinit. Add a "load("del_cline_prop.il")"
 ;               statement to your allegro.ilinit.
 ;
 ; To execute: Within the Allegro editor type "dprop" or 
 ;               "del cline props". This routine should
 ;               only take seconds to complete.
 ;               
 ; Deficiencies: This routine does not allow for Window or
 ;               Group selection. 
 ;
 ; WARRANTIES: NONE. THIS PROGRAM WAS WRITTEN AS "SHAREWARE" AND IS
AVAILABLE AS IS 
 ;              AND MAY NOT WORK AS ADVERTISED IN ALL ENVIRONMENTS.
THERE IS NO
 ;              SUPPORT FOR THIS PROGRAM.
 ;
 ; Delete invisible cline/via properties.
 ;
 axlCmdRegister( "dprop" 'delete_cline_prop)
 axlCmdRegister( "del cline props" 'delete_cline_prop)


 (defun delete_cline_prop ()
   ;; Set the Find Filter to Select only clines
   (axlSetFindFilter ?enabled (list "CLINES" "VIAS")
                     ?onButtons  (list "CLINES" "VIAS"))

   ;; Select all clines
   (axlClearSelSet)
   (axlAddSelectAll)     ;select all clines and vias

   (setq clineSet (axlGetSelSet))
   (axlDBDeleteProp clineSet "SYMBOL_ETCH")      ;Remove the property
   (axlClearSelSet)                              ;unselect everything
 )

-----Original Message-----
From: icu-pcb-forum-bounce@xxxxxxxxxxxxx
[mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx] On Behalf Of westfeldt
Sent: Tuesday, January 17, 2006 6:26 PM
To: icu-pcb-forum@xxxxxxxxxxxxx
Subject: [PCB_FORUM] components with attached routes

I'm revising someone else's board, and find that when I try to move or
copy
components, it takes some routing along with it, both traces and vias.
Seems like it is mostly fanout, but some long routes are attached as
well.
Board was done in Expert and I have Performance option.  Anybody know
what
these associations are, and how to break them up?

Patrick Westfeldt, Jr.
North Boulder Circuit Design
westfeldt_nbcd@xxxxxxxxx
720-406-0887
c 720-272-5822


-----------------------------------------------------------
To subscribe/unsubscribe: 
        Send a message to icu-pcb-forum-request@xxxxxxxxxxxxx
        with a subject of subscribe or unsubscribe

To view the archives of this list please login at
http://www.freelists.org. Our list name is icu-pcb-forum
or go to http://www.freelists.org/archives/icu-pcb-forum/

Problems or Questions:
        Send an email to icu-pcb-forum-admins@xxxxxxxxxxxxx

Want to post a job listing ?  DON'T DO IT HERE!  
Better yet, join our jobs listing forum.

SUBSCRIBE:  icu-jobs-forum-subscribe@xxxxxxxxxx
POST:       icu-jobs-forum@xxxxxxxxxx
-----------------------------------------------------------

Other related posts: