[PCB_FORUM] Re: Using an "Electrical CSET" vs a "Constraint Set" for diff pairs...

Hi Gerry,

Interesting to note the export "issue", thanks.

Regards,

Austin
  -----Original Message-----
  From: icu-pcb-forum-bounce@xxxxxxxxxxxxx
[mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx]On Behalf Of Gerry Meier
  Sent: Wednesday, March 26, 2008 3:52 PM
  To: icu-pcb-forum@xxxxxxxxxxxxx
  Subject: [PCB_FORUM] Re: Using an "Electrical CSET" vs a "Constraint Set"
for diff pairs...


  Yes, they are listed when you do a "Show element". However, not are listed
as properties and cannot be exported as properties by export netlist with
properties, unless you specifically add them as a property to the net













  Gerry



  Gerry Meier, Sr. PCB Designer

  Freedom CAD Services. Inc

  Voice: (256)776-7470 or (603) 864-1350

  Email:gerry.meier@xxxxxxxxxxxxxx

  visit us at http://www.freedomcad.com






----------------------------------------------------------------------------
--

  From: icu-pcb-forum-bounce@xxxxxxxxxxxxx
[mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx] On Behalf Of Austin Franklin
  Sent: Wednesday, March 26, 2008 4:31 PM
  To: icu-pcb-forum@xxxxxxxxxxxxx
  Subject: [PCB_FORUM] Re: Using an "Electrical CSET" vs a "Constraint Set"
for diff pairs...



  Hi Gerry,



  Yes, I thought that was what Gary was asking as well.  I posted how TO do
it and was just wondering if there was a way to do it with CM.  As a note,
when you put the diff pair phase tolerance in the spreadsheet, it actually
attaches a property to the net.



  Best Regards,



  Austin

    -----Original Message-----
    From: icu-pcb-forum-bounce@xxxxxxxxxxxxx
[mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx]On Behalf Of Gerry Meier
    Sent: Wednesday, March 26, 2008 2:08 PM
    To: icu-pcb-forum@xxxxxxxxxxxxx
    Subject: [PCB_FORUM] Re: Using an "Electrical CSET" vs a "Constraint
Set" for diff pairs...

    Austin,



    "I'm not asking how to do anything", I thought someone (Maybe Not You)
was asking how to handle different trace width and gaps for diff pairs. This
works in 15.2 all the way through 15.7. There are parameters that need to be
in CM spreadsheet or an Ecset like min line width, tolerance settings.



    Gerry



    Gerry Meier, Sr. PCB Designer

    Freedom CAD Services. Inc

    Voice: (256)776-7470 or (603) 864-1350

    Email:gerry.meier@xxxxxxxxxxxxxx

    visit us at http://www.freedomcad.com






----------------------------------------------------------------------------

    From: icu-pcb-forum-bounce@xxxxxxxxxxxxx
[mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx] On Behalf Of Austin Franklin
    Sent: Wednesday, March 26, 2008 2:52 PM
    To: icu-pcb-forum@xxxxxxxxxxxxx
    Subject: [PCB_FORUM] Re: Using an "Electrical CSET" vs a "Constraint
Set" for diff pairs...



    Hi Gary,



    > I'm not sure how to handle a different trace width and spacing within
the pair for inner layers as opposed to outer layers.



    I use Setup/Constraints and under "Physical (lines/vias) rule set" I use
"Set values..." and create a new Constraint Set Name, and set the values for
each layer there.  Close that, then use "Attach property, nets..." and
assign the attribute "NET_PHYSICAL_TYPE" to all the nets I want to control
with this constraint.



    That's the only way to do different trace width/gap on different layers
that I know of in Allegro 15.2.  Is that what you were asking?



    Unfortunately, I don't always have the luxury of having the same
width/gap for inner and outer layers.



    Regards,



    Austin

      -----Original Message-----
      From: icu-pcb-forum-bounce@xxxxxxxxxxxxx
[mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx]On Behalf Of Macindoe, Gary
      Sent: Wednesday, March 26, 2008 1:18 PM
      To: icu-pcb-forum@xxxxxxxxxxxxx
      Subject: [PCB_FORUM] Re: Using an "Electrical CSET" vs a "Constraint
Set" for diff pairs...

      Hey Austin,



      You know, I've wondered about that. Luckily I haven't had to deal with
it yet.

      One reason is that lately I only have top and bottom as routing
layers.

      I think the last time I had inner layers, the stack-up was designed to
have the trace widths/spaces the same for inner and outer for all
impedances.



      Here's how I handle it now for only outer routing layers, on 15.5.1:



      -          I set up the diff pairs using Logic -> Assign Differential
Pair, Auto Generate



      -          I set the trace width, spacing etc. for the pairs in CM



      -          I create a Spacing Constraint Set for each impedance (i.e.
"90DIFF" for USB) with the "Line To Line" set to the spacing required pair
to pair



      I'm not sure how to handle a different trace width and spacing within
the pair for inner layers as opposed to outer layers.



      I would suggest, if you can, to design the stack-up to have the widths
and spacings the same for outer and inner.

      That's the easy way out!



      Maybe setting up constraints, including diff pairs, is easier in 16, I
hope so.



      Good luck, I'm curious to see if anyone has the solution to this.





      Gary E. MacIndoe
      PCB Design Engineer
      Fort Collins, Colorado

      amd.com

      gary.macindoe@xxxxxxxxxxxxxxxxxxxx Message-----
      From: icu-pcb-forum-bounce@xxxxxxxxxxxxx
[mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx] On Behalf Of Austin Franklin
      Sent: Wednesday, March 26, 2008 12:39 PM
      To: icu-pcb-forum@xxxxxxxxxxxxx
      Subject: [PCB_FORUM] Using an "Electrical CSET" vs a "Constraint Set"
for diff pairs...



      Hi,



      There appear to be two ways to get the diff pair spacing and gap, but
only

      one allows differing them by layer.  Setting up an "Electrical CSET"
only

      seems to allow one overall (as in for all layers) space/gap.  But, the

      advantage of using the ECSET is you can assign it to a net or multiple
nets

      using the Constraints Manager spreadsheet using a pulldown menu.



      Or, I can setup a "Constraint Set" and select each layer's
space/gap...but I

      then have to attach this as a property to each and every net manually
by

      selecting the nets and attaching this Constraint Set name as a

      NET_PHYSICAL_TYPE attribute.



      I prefer the Constraint Set, since it gives me the per layer
control...but

      the thing that seems to be missing, is the ability to assign a given

      Constraint Set to the nets using the Constraint Manager spreadsheet.



      I'm on 15.2.  Am I missing something?  If not, has this improved on
15.7 or

      16?



      Regards,



      Austin



      -----------------------------------------------------------

      To subscribe/unsubscribe:

      Send a message to icu-pcb-forum-request@xxxxxxxxxxxxx

      with a subject of subscribe or unsubscribe



      To view the archives of this list go to
http://www.freelists.org/archives/icu-pcb-forum/



      Problems or Questions:

      Send an email to icu-pcb-forum-admins@xxxxxxxxxxxxx

      -----------------------------------------------------------




    This correspondence and any attachments are considered confidential. If
you are not the intended recipient, please notify Freedom CAD Services, Inc.
immediately by either replying to this message or by sending an email to
operations@xxxxxxxxxxxxxx; please destroy all copies of this message and any
attachments. Thank you.


  This correspondence and any attachments are considered confidential. If
you are not the intended recipient, please notify Freedom CAD Services, Inc.
immediately by either replying to this message or by sending an email to
operations@xxxxxxxxxxxxxx; please destroy all copies of this message and any
attachments. Thank you.

JPEG image

JPEG image

GIF image

Other related posts: