Thanks for the reply Shirley. We use LP Wizard for our physical symbol creation and it typically puts an array pattern of squares for the thermal pad paste. These squares are shapes, and can then be edited on an as needed basis in the design. Regards, Gary MacIndoe Senior PCB Design Engineer EbD R&D Hardware Surgical Solutions Group Covidien 5920 Longbow Drive M/S A20 Boulder, CO 80301 303.476.7458 www.covidien.com From: icu-pcb-forum-bounce@xxxxxxxxxxxxx [mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx] On Behalf Of Bolman, Shirley H Sent: Wednesday, January 25, 2012 7:34 PM To: icu-pcb-forum@xxxxxxxxxxxxx Subject: [PCB_FORUM] Re: Thermal Pad vias-to-gnd plugged? A workaround that we use is to not put the Pastemask or Soldermask definition in the padstack. Instead we add Pastemask_top and Soldermask_top shapes the same size as the thermal pad in the physical only. This way the Layout team can modify those shapes as they need for via placement and we do not have to create multiple physicals with different via placements. Shirley Bolman It is a PRIVILEGE to be born Free It is a RIGHT to live Free It is a DUTY to die Free From: icu-pcb-forum-bounce@xxxxxxxxxxxxx [mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx] On Behalf Of Douglas Stanley Sent: Wednesday, January 25, 2012 4:38 PM To: icu-pcb-forum@xxxxxxxxxxxxx Subject: [PCB_FORUM] Re: Thermal Pad vias-to-gnd plugged? Yes, we are concerned about this issue. The more vias you have in your heat slug, the more paste gets sucked in. It can cause a soldering problem due to the lack of paste that remains on the pad. We have two ways to approach it: 1. Have the PCB shop plug the vias with epoxy and then overplate them with copper. All of the vias are then completely closed. 2. Add a matching copper pad to the bottom side of the board along with corresponding mask and paste features. This won't stop the wicking, but we hope it mitigates it to some degree since we're adding a big dollop of paste on the opposite side. I'm in the process of writing a Skill program to find these issues on boards. Fab houses have a real problem with this, not only with heat sinks, but vias that fall into any mask opening that exist on only one side of the board. Douglas G. Stanley PC Board Designer, Principal Broadcom Corporation<http://www.broadcom.com/> - Irvine, CA dstanley@xxxxxxxxxxxx (949) 926-5889 From: icu-pcb-forum-bounce@xxxxxxxxxxxxx [mailto:icu-pcb-forum-bounce@xxxxxxxxxxxxx] On Behalf Of Macindoe, Gary Sent: Wednesday, January 25, 2012 2:50 PM To: icu-pcb-forum@xxxxxxxxxxxxx Subject: [PCB_FORUM] Thermal Pad vias-to-gnd plugged? Hey guys, When you have an IC with a thermal pad (e.g. A/D), the typical requirement is to put vias in the center pad that is connected to the gnd plane for heat wicking. Do you worry about the solder paste going down the vias, even with a 10 mil drill? My coworker is concerned that this will happen. I haven't had this concern, have never "plugged" etc. the vias with no negative feedback. Regards, Gary MacIndoe Senior PCB Design Engineer EbD R&D Hardware Surgical Solutions Group Covidien 5920 Longbow Drive M/S A20 Boulder, CO 80301 303.476.7458 www.covidien.com